Creating a Rivet Hole Chart in Autodesk Inventor.

In my adventures taking aircraft maintenance classes at Mount San Antonio College, I've learned a lot of things.  Not the least of which, is how much I have to learn!

Another piece of knowledge I'm grateful for, is how to drive and set solid rivets.  I'm not the best at it, but I can do it, and practice will make me better.

A sample rivet plate

One thing about riveting has been indelibly etched in my brain.  Rivets require precise holes to be properly fitted.  So much so, that a rivet is often referred to by the drill used to make the hole it fits in. 

For example, a "30" rivet is a 1/8 diameter rivet, and  uses a #30 drill for it's pilot.  A "40" rivet is 3/32 in diameter, and uses a #40 drill for it's pilot.  

A sample of the hole size for standard Imperial Rivets.
From EngineersEdge

If you're inclined to read about it in detail, you can find the specs at Engineer's Edge here, or in the Advisory Circular AC43.13 from the FAA here (start at page 4-14)

Merging that knowledge with my Autodesk Inventor knowledge, I found myself thinking, "How can I capture that knowledge?". 

My thoughts turned to the clearance hole table, which is maintained by an Excel file named Clearance.xls, can contain the new information I wanted to add.

I thought I'd share the steps I used for adding these holes.  Perhaps this is something you can use to adapt your own special clearance holes.

There are two types of clearance holes, the universal rivet, and countersunk rivet.  Basically, that means I need a countersunk hole, and a straight hole. I won't be using counterbores for rivets.

Universal Head Rivet
From Aircraft Spruce

A countersunk rivet
From Aircraft Spruce

So let's get started.

The first step?  Close Inventor.  This will make sure that when you place a hole, you're reading in the latest clearance table.  I also ran into errors when I tried placing holes with the clearance table open.  Something to do with Excel locking the file.

Locate the clearance.xls file.  It's location can vary, but it's set either in the Design Data location in Application Options, or Design Data in the Project.  Remember that if the path is set in the Project file, it will take precedence over the Application Option setting.

The Design Data location set in Application Options. 

The Design Data location set in the project. 

When you find the location, look for the ...Design Data\XLS\en-US sub directory.  It will have the Clearance.xls file you're looking for.

Before doing anything else, make backup of the original Clearance.xls file.  Just in case it gets go horribly wrong, the backup provides a safe haven to go back to and try again.

The location for Clearance.xls.  Notice I've also got a backup Clearance.orig.xls

Next, it's time to edit the Clearance.xls file and add in the new values.

Looking at the sheet, there are several columns, and it goes without saying that each does something. Some will be more obvious than others.

A sample of one of the charts in the Clearance.xls chart.

From left to right, here they are.

1. Fastener Type - This is a description of what type of fastener you're using the hole for.  This is the value you select in the hole dialog box. 
2. Size - This can be called the "nominal' name for the clearance hole.  In other words, if you're describing this fastener or clearance "in the shop" what are you asking for?
3. Shaft Diameters - This includes diameters for Loose, Normal, and Close fits.  Very typical diameters for many fasteners. 
4. Head Dimensions - This is broken down in to three columns that require clarification on their own. 
1. Diameter - The diameter to accommodate a fastener's head. 
2. Depth/Angle - This is the depth required to clear the head, or if a countersunk fastener, the angle of the head. 
3. Head Type - What type of fastener this is.  The number "2" designates a countersunk head.  A "1" designates a 'standard" head. 

Armed with that knowledge, it's time to setting things up!

The easiest thing I found to do is copy one of the existing sheets.  It can serve as a template to create the new table.

Copying the Excel table

So now the table is copied, we understand what the columns do.  It's time to start editing.

Most of this is just taking the values from the standards and copying them into the tables. But I am going to use a couple of tricks to get the table to do what I want.

For starters, rivets don't have close, normal, or loose fits, there's really just one proper nominal dimension.  So I'm going to set the the values to close, normal, and loose to the same thing.  That way, no matter which the end user chooses, they get the right one.

Also, I'm not using counterbores with my universal rivets. In order to make that "unselectable", I'm going to set the counterbore diameter to be smaller than the shaft diameter.

Making the counterbore diameter smaller than the shaft diameter will force the counterbore to "error out" if someone tries to use it.  It's not fancy, I know, but it will work.   I can always change it later too!

My creation. The rivet clearance chart for Inventor

That's the big part, but now there's a couple of more details left.

I'm going to set the "Sort Order" to make sure that the tab appears where I want it.  This affects the order in which the table appears in the hole dialog box.  Just like the name describes, 1 is first, 2 is second, etcetera, etcetera.  (A guy with my haircut has to use that reference!)

I'll also rename the sheet to something meaningful to someone using it.  You know, like "Rivet Clearance".  It took me a while to come up with that one!  (sarcastic grin).

Changing the Sort Order, and renaming the table.

Once this is done, fire up Inventor, and test out your new table of date!  Now you're ready to go!  You can see where the Table Name, Fastener Type, and Size appear in the hole dialog box.

Placing the Rivet.  Notice how the names (circled) correspond to the Clearance.xls table.

Now, it's time to "serve and enjoy" your new chart.  And don't forget to make a backup of this data too!  There's nothing worse than doing it twice.

Even if you can't use it for rivets, perhaps you can adapt this for something else!

A Guest Post! Configure Open File Behaviors - New in Autodesk Vault 2016

So much has been added in the 2016 Autodesk releases, it's hard to keep track of them all.

That's where a great team comes into play.  I'm happy to share this post by Jonathan Kriek of KETIV  This post originally appeared on the KETIV blog, Side Note.

In this post, he discusses the Open File Behavior that's been added to Autodesk Vault 2016.  I'm looking forward to checking this one out myself!

So without further delay, here you go!

Configure Open File Behaviors - New in Autodesk Vault 2016
By Jonathan Kriek

A fair amount of users most likely have more than a couple versions of AutoCAD and/or Inventor installed on their system. This may be due to testing the latest version, while production requires the previous or having other business system requirements that force them to retain an older version.

My reasons are simple - providing all inclusive support to our customers by being able to troubleshoot multiple versions simultaneously. But regardless of why the fact remains that by default until now Autodesk Vault used MS Windows settings for determining which [version of a] program to open for a given file type (except 2015R2 for subscription customers which includes some early 2016 functionality).

Autodesk Vault 2016 now gives you greater flexibility in choosing which version of your Autodesk software to open.

What Autodesk software and file types are supported?

Currently "Open File Behaviors" support the following Autodesk software and file types:

• Autodesk Inventor
• IPT, IAM, IPN, and IDW
• Autodesk AutoCAD
• DWG and DXF
• Autodesk Revit
• RVT, RFA, and RTE

How do I access Open File Behaviors settings?

In the Vault Client, select Tools > Options.
Next to Open file behavior settings click "Settings".

Open File Behavior configuration options

Depending on the CAD application, you can determine whether CAD files are opened by the latest version, the last run version, or the version of the CAD Application that last saved the file.

• Last Run Version (Inventor Only):
• This option will open the CAD file with the last used version of the CAD application.
• Latest Version (AutoCAD and Revit Only):
• This option will open the CAD file with the newest version of the CAD application installed.
• Saved by Version (AutoCAD and Revit Only):
• This option will open the CAD file with the version of the CAD application that was last used to save the file.
• Default
• This option uses the current settings in Vault for opening a specified CAD file.
• Autodesk Inventor files are opened with the default application specified by Windows.
• AutoCAD files are opened with the latest version of Autodesk AutoCAD installed.
• Revit files are opened with the latest version of Autodesk Revit installed.

Example scenarios

These settings are pretty straightforward and not all options are available for each CAD application, but let's take a look at a few examples.

If Revit 2015 and Revit 2016 are both installed on your machine, and you want files that were saved in RVT 2015 to always open with RVT 2016, you can configure Vault to always launch Revit 2016 for all .RVT, .RFA, and .RTE files by choosing "Latest Version".

If AutoCAD 2014 and AutoCAD 2015 are both installed on your machine, and you want files that were saved in ACAD 2015 to open with ACAD 2015, and files saved in ACAD 2014 to open with ACAD 2014, you can configure Vault to always launch the "Saved by Version" of AutoCAD for all .dwg and .dxf files.

Final Thoughts

The Open File behavior finally applies some adaptability to the process of opening files and determining whether CAD files are opened by the latest version, the last run version, or the version of the CAD Application that last saved the file. I hope you found this article and the new Vault 2016 Open File functionality useful!

Jonathan Kriek

Importing and Exporting Your Autodesk Inventor Settings

A few weeks ago, I had an opportunity to write for the CAD Setter Out.  In that post that you can find here, I wrote about some of the settings that I like to change in Inventor's Application Options.  These are settings I change on any new install of Inventor I'm going to use.

These are my settings of choice.

Not too long after writing the post, I found myself working offsite for a few weeks.  The computer I was using wasn't mine.  It was a loaner.

So I did what I always did, I set up my Inventor installation just the way I wanted.  All was good the first day. 

But when I returned the next day, after rebooting the computer, I found that my Inventor installation had returned to default.  I had to reset everything!  And while this too a few minutes, it was a nuisance. 

The IT department knew it was likely something in the windows profile, but they had their own set of challenges: 

• They were in the middle of upgrading some of their own systems, so they had limited time for me
• My issue only took a few minutes for me to fix, so it was far from a "show stopper". 
• I was only going to be onsite for a short time.  

Given those factors, it's understandable why they didn't jump on my issue.  

That meant finding a way to do the best I could with what I had. 

Thankfully, I was able to draw on a trick that made this issue much less challenging.

I thought it might be worth sharing.  I hope you agree! 

All you have to do is export your settings to an XML file.

So let's get started! .

The first step is to setup your Application Options just the way you want them.  This is just like you've likely done before.

Remember, these are found on the Tools ribbon. 

Some of my preferred Application Option settings

But now, select the Export button.  Choose a location and save the XML file with your default settings to a safe place.   In my case, I just saved it to a folder on the desktop of my machine.

Exporting the settings to a preferred location

You might consider putting it on a USB stick, or on a cloud account like Dropbox, Copy, or A360 Drive.  You could even e-mail it to yourself.  As long as it's someplace you can find later.

After my computer had restarted, and Inventor had again returned to default, I was able to go back to my application options and import my preferred settings.  In a few minutes, Inventor was set back the way I liked it!

Importing the settings back into Inventor

What's the big benefit?   You can walk up to any machine and bring your settings with you.  It can make setting you machine up much easier.

In my case, it gave me a quick way to restore my settings until the IT department was able to tweak my user profile, rendering the issue moot.

I must add one disclaimer however, or else I'd be doing you a disservice.  I've not tempted this particular fate myself, but I have on good authority that this doesn't work well for migrating customizations.

In short, new tools, ribbons, and options may exist when a new version of Inventor is released.   A settings file from a previous version may not know how to address these new settings.  As a result, they may not work correctly.

So in other words, just use it across the same version, and all should be fine.

In any case, keep this in mind in your own uses.  Any time you need to bring in your preferred settings to Inventor, have this at the ready, and you can have your preferred settings at your finger tips!

Also, if you expand the flyout under the import button, you'll see Use AutoCAD Related Settings, which will set Inventor's appearance to mimic AutoCAD, such as having a black background in the modeling environment .

There's also Use Inventor settings.  This resets Inventor to its default settings.  Good things to know if you're experimenting with settings!

Inventor's alternate settings

So take these settings and see where you can use them!  Maybe it can help you! 

Preparing Your Autodesk Inventor Project File for Inventor 2016

In an earlier post, I discussed installing your new suite of Autodesk software.  But then comes configuration.  There are things that have to get setup and configured.

After installation, on of the next things I like to do is migrate my Inventor project file to make sure it's set up for the new software release, in this case Inventor 2016.

Every installation is a little different, so first, I'm going to discuss a few things that are unique to my installation.  You may not encounter all these, so you might change a few steps based on your own installation.

It all revolves around one thing.  I have to run multiple versions of Inventor, as far back as version 2012.  That means maintaining previous versions of  template files and the Design Data folders.

In order to accommodate this, I need to use a project file for each version of Inventor I run, that allows me to point each version of Inventor to its own template and design data folders.

That means copying and pasting of template and design data directories in Windows explorer.  I also copy my custom material and appearance libraries to this directory.

And by the way, it's a good idea to make a backup copy of these files.  You'll have options to try a few things if you want, and recover from any mistakes.  "One and done" is what we aim for in a migration, but reality has a way of getting in the way of the best laid plans.

Once the design data and templates are copied, it's time to copy my project file.   I'm renaming it to Arduinna 2016.ipj so I know which version of Inventor it belongs to.

All of this goes pretty quickly.  It's just the standard Windows copying and pasting.

Once that is done, it's time to tell Inventor 2016 to start using the project.

Inside of Inventor, choose Projects on the Get Started tab.

Once the dialog box opens, browse out to the directory the copied the project file. Select it and select open.  The project will read into Inventor, and be set as the active project.

Now it's time to point the project to the locations it needs to use.

I like to set my locations with in the project, which means I start out in the "Folder Options" section of the project.

So in my case, I point the Design Data, and Template folder locations to the directories holding the files that are going to be used in Inventor 2016.

In addition to that, I want to add my Material and Appearance Libraries to the project as well.  So that means right clicking on each library, and adding the ones I want.

Once this is done, setting up the project is done.

But before we can start firing up our new project, you'll have to migrate the templates and design data for your new project.
Fortunately, the process hasn't changed from previous releases, so you can reference my posts here from last year.

Here's my post for migrating Design Data, and here's my post for  migrating templates.

And there you have the steps to migrate a project.  Don't forget that depending on your setup, you may not follow the exact same steps.  The key is making sure the steps are done for your configuration.

Don't be afraid to run a couple of tests (that backup can come in handy for that!), and make sure you cover your bases!

Autodesk Inventor 2016 - The "What's New" Trailers

For the last week and a half, I've been working full time on a customer site.  And while it's good to be busy, it's a bit tough on the blogging schedule.

But with the help of the KETIV Technologies team, I have been able to lend my voice to a few what's new videos for Inventor 2016.  

They're what I'd call "previews", but they do give you an idea of what some of the new capabilities are!

I've included them below!  And I'm still planning on creating more posts! Just give me a little time! 

But take a look at these videos for a tour of what's new in the latest release of Inventor! 

Part Modeling Enhancements 

If there's anything that gets used a lot, it's part modeling features. Take a look at some of the new ones here! 

;

T-Splines Enhancements

If you need to create organic shapes, this is the tool to take a look at! Notice how you can create symmetrical shapes with just a few mouse clicks1

;

Sheet Metal Enhancements

Tools like automatic thickness detection, zero bend radii, and multi-body support are now in the tool box for Inventor 2016 sheet metal! 

;

Presentation File Enhancements

These enhancements have been much requested!  There's a lot of improvements, from the interface, to View Representations, a lot of wishes have been answered. 

;

Home Screen Enhancements 

First introduced in Inventor 2015, The home screen has had more features added to it.  I'm a fan of the filters for recent files, but there are more enhancements than just that. 

;

Electromechanical Improvements

Better communication between Inventor and AutoCAD Electrical is the name of the game.  Here's where you can see a bit of them working together. 

;

DWG Underlay

Do you need to reuse your AutoCAD drawings in Inventor?  Do you want to maintain a link between the two?  You've come to the right place!  Check this out! 

;

Documentation Enhancements

Inventor drawings received quite a shot in the arm this release!  View creation is new and streamlined, text creation has been enhanced, and transparent parts are just cool. 

;

Assembly Feature Enhancements

Do you want to replace more than one part at a time?  Do you need to tweak your install for better performance? Or maybe you just want to zoom in to your interferences, or have a more options for component patterns.

Take a look here! 

;

Additive Manufacturing Enhancements

"Enhancement" is probably an understatement here, entire sets of tools have been added that didn't exist in previous versions of Inventor.  Everything from splitting large parts to fit in a small machines, to having envelopes for different machines available.

;

So there you go!  Your epic tour of the new features in Autodesk Inventor 2016.  

Time to start Inventing! 

Installing Your Brand New 2016 Autodesk Suite

Work has been picking up again, which is good!  Being busy beats not being busy for sure!

But this weekend, I did find time to install my 2016 Suite, in this case, Factory Design Suite Ultimate.  I had the foresight to record the steps too! . 

But like so many things, the preparation can't be overlooked.   To make your steps go as smoothly as possible, make sure you've done the following before getting started. 

1. Make sure you have Local Admin rights!  You won't get far without them! 
2. Turn off your Antivirus.  I don't see too many AVs stop an install now, but I have seen cases where the antivirus will slow the install as it checks the install files. 
3. Turn of User Account Control.  I've seen it cause issues, and I hate that thing on any Windows OS I've used. 
4. If you're running a network licensed version, make sure you have your new license files.  Nothing is more frustrating than getting the install  finished, and realizing you haven't updated your licenses yet! 
5. On that same vein, if your using Autodesk Vault, have you updated it yet?  Consider upgrading your server first!  You can't use your 2016 products with a 2015 Vault.  A little planning goes a long way.  Check out my post here for info on that! 
6. Give yourself time! These installs take a while.  That's a fact.  You don't do it "in a few minutes".  I've had to leave my laptop at the office because it was only 50% done at 5:30PM.  Don't make that mistake, give yourself a few hours to get it done properly. 
7. And if there's any doubt, as your admins, your cad manager, or check the Autodesk Inventor discussion groups!  A little clarification goes a long way! 

So you've done your planning, and now you're ready to install.  Go ahead and click on your Setup.exe and let the installation initialize. 

Soon you'll see the intro screen with the Deployments, Create Deployments, and Install buttons.  I'm going to just install my Factory Design Suite directly, so I'm just going to choose Install. 

The next page you'll see is the End User License Agreement (EULA), you have to accept it, or else your journey ends here.  Click yes, and click the Next key. 

Now, to choose a if you're using a Network, or Standalone license.  A Standalone (node locked) licenced machine hosts it's own license. This is often found on laptops that are aren't always connected to a network. 

Network licenses check out their licenses from a central server, like a book from a library.  

I won't go into the details of each, but it is important to know which one your installing right now . If your not sure, check with your CAD Manager, or your friendly neighborhood reseller.  

You'll also enter your serial number and product key here.  If you don't know what they are, there are instructions on how to locate them here.  Once you have everything you want, you guessed it, hit Next. 

There's one more screen before the big time! It's time to choose which products to install, assuming you want to pick and choose. 

There's several things you can do with this screen.  As indicated by the arrows...

1. Click the arrow to expand the screen and choose options for a given products, such as configurations, settings, and to download and install additional updates.
2. The arrows will display additional information.  For example, content center libraries are available to download now. 
3. Finally, change in the install directory if you'd like to install somewhere other than default.  Such as a drive different than C:

Once you've set all these options, you can choose Install.  At last! 

This is the part that can take a while.  Give yourself a couple of hours for the install, more if you're going to remove old products.  It takes time, so be prepared. 

After waiting it out, you'll be rewarded with the sweet sight of success!   

Now, you're ready to migrate styles, and get your new suite ready to use! 

:

A Post for KETIV - Walking Through History at the Planes of Fame Airshow.

For those of you who know me, even if it's only via the Internet, it's no secret that I like vintage aircraft.  I find the stories about them fascinating, and the people who designed, built, flew,and maintained them fascinating too.

The Grumman F7F Tigercat in front.  Two Vought Corsairs in the background.

Last week, my bosses at KETIV Technologies asked me to write a blog post on the Planes of Fame airshow, and I found myself struggling with quite the case of writer's block.  So much to say, and how to say it.

Fortunately, I was able to put thoughts to virtual paper, and come up with something, and now it's been shared to the KETIV website.

So rather than repost it here, go ahead and follow the link to the KETIV blog here.

I hope you enjoy the article, and here's a couple of bonus pictures for passing through my blog on the way there! :) 

A Douglass C-47.  A loyal, dependable, workhorse of an airplane.

A Lockheed P-38 Lightning, of World War 2 fame, taxiing between two
North American P-51 Mustangs after a flight.

Later on, a F-22 Raptor flew.  State of the art today, here it is taxiing back
between the same two Mustangs.

Springtime Changes! Upgrading to Autodesk Vault 2016

It's time to start my springtime upgrade to my Autodesk 2016 based products.  And I've decided to share my upgrade process again.  I hope that this helps you along your way as you consider your own upgrades.

I'm running Autodesk Factory Design Suite 2015, with Autodesk Vault Professional 2016.

Because of that configuration, I'm going to start with upgrading my server to Vault Professional 2016.

Why?  Vault Professional 2016 can run my 2015 and 2014 based products. So my new Vault server can support my 2014 and 2015 base products.  So if I can't upgrade Factory Design Suite right away, I can still access my Vault files.

You might think the next step is to click on that pretty, shiny, setup.exe file, but I would suggest considering a few things first.

• Check the server's system requirements.  Do you need up upgrade SQL?  Is there enough hard drive space?  Is the server's hostname "Wheezy", because that's an accurate description of it's current condition? 
• Do you have your Vault backed up?  And just because it was running fine the last time you checked, before going to the company Christmas party doesn't mean it still is.  Check again! 
• Consider running a test upgrade off line, if you have the capabilty.  And just because you've got a new server you've named NCC-1701 (you clever geek, you!), you might give Wheezy one last shot at glory before consigning to the Great Beyond.  Use it to test your migration off line! 
• Finally, if you have any network licensed products, like Vault Professional, for example, get those licenses ahead of time!  You're going to need them! 

I know preparation steps aren't fun, and they seem like a lot of extra work.  I rarely see a Vault migration go wrong, but the Titanic was making great time when it hit the iceberg.  You never want to be remembered as "the CAD manager who shut down engineering".

So now, the preparation steps are done. The backups are checked, verified.  Finally, it's time to run that backup.  

Now, click on the Setup.exe file that you've been getting excited about. 

Launching the Setup.exe

Once the setup initializes, run the precheck.  This is going to identify if there are any issues that need to be resolved before proceeding.

If you're used to 2015, the precheck has it's own button now

In my case, I did have an AutodeskDM directory already existing.  But if you get any error, click on the link.

Looks like we have a little fixing to do!

A list of possible solutions will appear.  I was able to resolve my issue by following the instructions listed.

Deleting the AutodeskDM directory per  the solution fixed my issue.

Run the precheck again to make sure that all issues are resolved.  Once the precheck is clean, click Install.

Now, we install! 

Next up is the End User License Agreement, or EULA.  Accept it and move on.  That's pretty much all there is here! 

Read this carefully (I know you do!), accept and continue!

After accepting the EULA, it's time to enter your serial number, product key, and if you're using  Vault Workgroup, or Vault Professional, your license server. 

Entering the information you need,. 

Clicking the next button will now ask you if you want to install with a new configuration, or with the previous configuration from your existing Vault. 

In my case, I'm using my previous configuration, so I choose that. 

Do you want to use the new configuration or default? 

Now, Vault will ask you which components to install, as well as what location your going to install to.  In my case, I'm using my D drive, so I change the install location. 

Now we get to hit the button we've been waiting for, Install.  (Cue music to 2001)

All I need to do is change my location here.

There's one more advisory that appears.  Vault tells us that it's detected an existing database, and in order to be useable, we're going to have to migrate it. 

This is just advising you that you'll need to\
igrate your existing database to make it useable. 

In this case, the point is to migrate it, so we'll say yes.

The install goes for a few minutes, depending on your machine.  The installer will run prechecks again, removed the old Autodesk Data Management Console, and install the 2016 version. 

Now we wait for the install.

Once the installer completes, you'll see your "Success" screen.  Take a second and pat yourself on the back!

If you're migrating an existing Vault, as I am here, You'll see another message to open your ADMS Console to migrate your databases.  It's a good idea to do that now. 

Starting the console to star the database migration.

The Autodesk Data Management Console will open and ask you to log in, and begin migrating the necessary databases. 

This is the process of migrating.  This can sometimes take a while for
large datasets.

 One more message is going to come through.  Vault is going to ask if I want to migrate my Vaults and custom libraries.  Which in this example, is what I want do to, so I'll answer yes. 

Choosing which databases to migrate.

One more question comes up, and it's one worth noting. Vault is going to ask which versions of Inventor you want to have your custom Content Center  Libraries available for.  In my case, I work with Inventor 2014, 2015, and 2016, so I'll  keep all three.

This is a good time to get rid of any unused libraries, it will make backups run a little quicker, and will save a little hard drive space.

Which versions of Inventor do you want your custom libraries available for? 

Once this is accepted, the final migrations are complete, and everything is done.

Now, just reconfigure, and validate your backups, and you're ready to go on to the next step!

In my case, installing my 2016 based client software!

Stay tuned!

P.S. I'm hoping to build a video for this as well, but videos take a while to create, particularly this one!

Look for it to be added in a future date! 

A Little Side Project Now Shared on GrabCAD - The NutPlate iPart

Every so often I like to create content just for the fun of creating it.

It does keep me practicing my Inventor skills, and sometimes, I just enjoy doing it.

One thing I've been doing over the course of the last few months has been creating some standard aviation style hardware.  I've created them as iParts, similar to I have in similar posts.

In this case, I've created a nut plate based on the part number NASM21047.  I found this data on the Coast Fabrication website, which I've found to be a great resource for these types of components

A sample of the nutplate iPart. 

I've created the parts using the same methods as in my post from a few months ago.  The steps are largely the same, so I won't recreate those steps here.  They're already in that post.

However, there are a couple of differences that are worth pointing out in this new version.

In this model, I've suppressed features in some of my iPart members.  This is because some of variations have a counterbore in the bottom, and others don't.  As a result, you'll see lines where the counterbore features, and the feature attached to them, are suppressed.

Features that need to be Suppressed for some family members can be added on the Suppression tab.

A Suppression Column.  I like to type out the words myself.

Suppression and compression of a feature by typing one of several values in the field.

Suppress a feature by entering one of the following:

• Suppress
• suppress
• S
• s
• 0

Compute (turn on) a feature with one of the following.

• Compute
• compute
• C
• c
• 1

I've also added a material column this time around, this makes sure the mass is accurate for each variation as well.

You can tell a column to be a Material column by right clicking on the header, and selecting the Material Column option.  Then type in the material you want in the field.

Notice the Material Column

Mostly, I just want to create a sample that you can use to get ideas how to create an iPart, or use this as inspiration to build your own iPart!

After all, why do the work if it's not going to be shared.  The iPart was built in Inventor 2015.

Take a look at the GrabCAD link here!  A login is required, but it's free! Download and enjoy!

Alternately, here's an another link to the iPart that doesn't require a login!

On one last note, I've done my best to make sure the dimensions are accurate, but there's always the chance I missed something.  It never hurts to check.

And if I missed something, let me know!  I'll do my best to correct it!